VSIN - Sinusoidal Voltage Source Model

Old Content - visit altium.com/documentation

Modified by Phil Loughhead on Mar 4, 2014

Model Kind

Voltage Source

Model Sub-Kind

Sinusoidal

SPICE Prefix

SPICE Netlist Template Format

@DESIGNATOR %1 %2 ?"DC MAGNITUDE"|DC @"DC MAGNITUDE"| SIN(?OFFSET/&OFFSET//0/ ?AMPLITUDE/&AMPLITUDE//1/ ?FREQUENCY/&FREQUENCY//1K/ ?DELAY/&DELAY//0/ ?"DAMPING FACTOR"/&"DAMPING FACTOR"//0/ &PHASE) #"AC MAGNITUDE"|AC @"AC MAGNITUDE"| @"AC PHASE"

Parameters (definable at component level)

The following component-level parameters are definable for this model type and are listed on the Parameters tab of the Sim Model dialog. To access this dialog, simply double-click on the entry for the simulation model link in the Models region of the Component Properties dialog.

DC Magnitude	DC offset used in an Operating Point Analysis. (Default = 0).
AC Magnitude	the magnitude of the source when used in an AC Small Signal Analysis. (Default = 1).
AC Phase	the phase of the source when used in an AC Small Signal Analysis. (Default = 0).
Offset	DC offset voltage of the signal generator (in Volts). (Default = 0).
Amplitude	peak amplitude of the sinusoid (in Volts). (Default = 1).
Frequency	frequency of the sinusoidal output voltage (in Hz). (Default = 1K).
Delay	delay time until the source voltage commences (in seconds). (Default = 0).
Damping Factor	the rate at which the sinusoid decreases/increases in amplitude (in 1/seconds). A positive value results in an exponentially decreasing amplitude; a negative value gives an increasing amplitude. A zero (0) value gives a constant amplitude sine wave. (Default = 0).
Phase	phase shift of the sinusoid at time zero (in Degrees). (Default = 0).

Notes

The image above shows an example waveform produced by a sinusoidal voltage source (connected to a 1Ohm load). The Delay has been set to 500.0u and the Damping Factor set to 250 - to illustrate a decreasing sinusoid. All other parameters have been left at their default values.
The shape of the waveform is described by the following formulae:

V(t₀ to t_D) = V_O

V(t_D to t_STOP) = V_O + VA e ^{-(t - t}D^)THETA sin(2πF (t + t_D))

where,

t is an instance of time
V_O is the DC offset voltage of the signal generator
V_A is the maximum amplitude of the output swing (excluding the DC offset)
F is the Frequency
t_D is the Delay and
THETA is the Damping Factor.

The simulation-ready sinusoidal voltage source component (VSIN) can be found in the Simulation Sources integrated library (\Library\Simulation\Simulation Sources.IntLib).

Examples

Consider the sinusoidal voltage source in the above image, with the following characteristics:

Pin1 (positive) is connected to net INPUT
Pin2 (negative) is connected to net GND
Designator is Vin
Frequency = 10k
All other parameters for the model are left at their default values.

The entry in the SPICE netlist would be:

*Schematic Netlist: Vin INPUT 0 DC 0 SIN(0 1 10k 0 0) AC 1 0